drop down to 14000 at 11 MPM. If you get a good result start working you're way up from there. If not, you probably have something loose in the head of the machine. Loose bolts?

Had this from day 1?

Try a different board.

Your comment about the board being bowed and not held down is also a huge red flag.

Unless you are running only large pieces, you should be using 2 flute as the acceleration curve of the machine may not get you up to 19mm/m on smaller parts.

Climb or conventional?

Is the chipping happening on the first or second pass?

Based on your board I assume you are in Canada. If you haven't done so already try FS Tool coated compression spirals. We tried another brand and got chipping on the top of the board.

With intermittent chipping I would first look at the spindle taper. Is it clean? Does it have any burrs or debris caught in it? If not, do the chips tend to be in the same location on the table or random?

First off it looks like my original post got messed up, it's missing some of the text at the top
Machine is a 2008 Weeke vantage 32S
I bought it used, but got Homag to set it up and completely go over the machine

To Cris:
I can try that, but that seems very low
Main spindle spins very nice and freely, and if something was messed up there then everything would be messed up and chipped, but on textured melamine its cutting clean except the entry cut.

To Dropout:
I used Panolam at first, but quit using that due to chipping, been using Uniboard instead with mixed results
What do you mean by climb or conventional?
No I haven't used FS tool bits yet, i suppose I could try that
My current supplier has gotten me to use every type of Royce bit out there, I'm not sure if FS Tool would improve things.
Chipping happens on first pass i believe, but i would have to double check that.

To Tom:
Good point, i should check the spindle for any dirt
The chipping is random all over

I spoke to Royce rep this morning and they said my feedrates etc look ok, they're going to look into it further

I'm at the point of returning all my stock of royce bits to the supplier and getting a different brand

I had an experience where I was getting chipping with RA coated bits but not FS.

Google climb cutting - will be better than me explaining. We climb cut first pass and conventional the finish pass. Do you do the first pass oversize? we do 0.5mm.

I do conventional for both cuts

No i don't offset the first pass, i know in my software it is an option, but i remember the tech support guy said" that's only for cheaply build machines that have deflection, a Homag shouldn't do that"
I wonder if i should try that though

I've been cutting melamine for a long time. My chip load target is 0.0185, meaning with a 3 flute bit I run 1000ipm at 18k. Reduce speed for 2 flute tools. The only time I have had chipping was due to my board supplier. Change that and the chipping went away. Good luck, but if the machine checks out and the spindle has been trammed properly, I guess its the board manufacturer.

To BH Davis: im going to give this a try soon
But given that my dado bit(which is a downcut) also chips the cheap white melamine
But i could indeed solve the entry chipping with that on the textured melamine.

To Mike: wow thats fast!! I feel like it'll be pushing my pieces around like crazy when I'm routering smaller pieces, haven't had bits breaking yet at that speed?

I use FS Tools uncoated compression bits with good results. I can run them until quite dull without chipping. I also cut Uniboard, Panolam Tafisa and others without chips. Mine is a lightweight cnc so my feedrates wouln't be of any use to you.
I don't think this is a board or bit issue. Royce bits are very good and if the sheet goods were a problem, there would be a whole lot of complaints coming in to your supplier.
I would be looking for machine faults.

i've complained to the suppliers about the chipping issue before, and you know what their standard response is right? "but sir, we've been having such good feedback on this product" they'll always deny that their product is at fault
another example: Uniboard sheets are always bowed the 4ft way, same response from the rep
none of them seem to tell the full truth or actually take it back to the manufacturer and do something about it

I guess my machine is 17 years old but relatively low hours, I thought Homag is a premium product?
their customer service sure isn't btw. absolutely useless!!

Gerben,
No bit breakage, but I have a very heavy machine with a 24hp spindle. We also have a 40hp oil ring vacuum pump. I have always thought that type of pump pulls a deeper vacuum than rotary vane style. I've used them both over the years. If you can't cut at those speeds, don't waste money on 3 flute tools. Stick with 2 flute tools and slower feed rate. For reasons I don't fully understand, I get a better cut on Ultralight MDF with 2 flute tools at the same chip load as with the 3 flute tool.

I also use a Komo with 16HP spindle and 40HP liquid ring pump.

My Komo is 16,000 pounds. My buddy's new heavy duty Biesse with more bells and whistles is 9,000 pounds. They are not the same.

To Mike:
Wow 24hp thats wild!!
Mine is half of that which i thought was pretty standard
My machine moves pretty fast though, but who knows, there's probably faster out there.
I use 2 becker vane pumps, 8hp and 9hp i believe, but only use the 8 when needed for bowed sheets or small parts etc.

3 flute can give better results i understood, but only if you go fast you're saying?

Dropout:
Mine is just shy of 8000lbs, Homag advertised it at the time as "fastest and heaviest machine in its class"
Brother of mine in Europe invents and build machinery, he was very impressed with the build quality etc.when he seen my Weeke Vantage

I did some testing today

first off I tried offset cutting, although I did get cleaner results, it somehow messes up the programming and causes the onion skin to be the correct size, but the main part is the wrong size

second I tried using 2 different bits, first up to the onion skin with a 2 flute downcut, and the onion skin with a 3 flute mortise compression, very nice results without chipping, but still a bit excessive onion skin showing
not sure how to fix this, I think it has to do with having each bit entered as a slightly different diameter, they're both 3/8" bits, but they never seem to be right at 3/8"

I also cut some dados for blind dado construction cabinets, but decided to router the dado a half mill deeper, instantly clean dado's, I guess that tells me that bit is dull right at the top of the dado, because I do all my dado's at 1/4" deep i'm guessing it's just worn too much right on that spot after 60-80 sheets